In this Solid Solutions video, I'm going to show you how to add exploded views and bills of materials to your SOLIDWORKS assembly from inside the online trial. To access the files used in this example from the online trial. Select the open icon from the SOLIDWORKS toolbar and navigate to the C drive Users photon User documents SOLIDWORKS Product Trial, sample content, Mouse Assembly, and double click the assembly file. When we first open the mouse assembly, we can see that the buttons have been made transparent, allowing us to see internally. This transparency can be quickly toggled on or off by using this arrow feature manager, which gives us information on its parts, visibility, display style appearance, and transparency. We can select the icon beside the mouse buttons, to make it opaque. Another way of examining the internals of an assembly, which also helps show how the assembly should be fitted together by creating an exploded view. To do this, we temporarily move components in the order that they would be assembled or disassembled and see if they're positioning in an easily accessible view, which we can also animate or bring into a drawing. To create an exploded view, select the icon from the assembly tab of the Command Manager. This will bring up the explode property manager for steps can then be created to move components. To do this, select the first component to move. In this case, we'll select the buttons. Our three default axes will appear and we can use the arrows to translate the buttons. Going to translate up in the y direction by dragging and dropping the arrow. When we do this, the information will fill in to the explode property manager, and we can fine tune the distance or degree of rotation if required, and then press done to complete the step. Multiple components can also be exploded at the same time. On the underside of the mouse. There are four contact parts. I'm going to select each one of these and then use the arrow to move them down in the negative Y direction. And again select them from the property manager. Next, the battery cover on the underside of the mice can be selected and as it is inserted from the side, I'm going to exclude it in the negative z direction. Previously we had completed the exclude steps I select and done in the property manager, but there are quicker alternatives when a part is dropped into position. A mouse icon beside the cursor appears with a blue arrow over the right mouse button. This means that if I right click now. The explode step will be completed. This can help save on mouse movement. Some parts are not best suited to using the default x, y, and z axis as a direction for their explode. If this is the case, we can drag the manipulator onto different Faces or edges and use those for reference direction. Selecting the mouse wheel, I can see that the default actors are shown as normal. There is a white ball in the center where they meet. Right click and drag this to an edge or face the direction. Okay, along that edge are normal to that is, I dropped the manipulator onto the edge. It wheel housing and drag the arrow. You’ve compleated this step. Final two components which need to be exploded are the bottom housing and on off switch on the underside of the mouse. Previously, we have exploded multiple components at the same distance in one step. However, we can also explode them in the same direction by different amounts. To do this, select the option auto space components from the Explode Property Manager. With this selected, we can drag the Y axis arrow to see the components moving, but at different rates. When we drop its components explode. Distance can be fine tuned using the individual arrows. Once this step is completed, all of the necessary parts have been exploded. However, if any changes need to be made, this can be done from the Explode Steps box on the property manager. And here select in any step gives a full list of options which can be modified. The order of the explode steps can also be changed. For example, if I prepared the mouse wheel to move. Second, I can click and drag explode. Step four to below explode. Step one. When happy with any modifications, use the green tech to accept the explode. The exploded view is stored in the Configuration Manager under the default configuration. From here we can right click and collapse or explode the assembly. We can also animate the collapse or explode to create a useful video showing how the part is to be assembled or disassembled. These videos can be saved as various extensions including .MP4 and .AVI. With our explode complete, we may wish to show it in a 2D drawer. This can easily be done by selecting the arrow beside the new icon, and make drawn from part assembly using the A3 sheet. When prompted, the view palette will automatically appear to the right of the screen for default views of the assembly previewed. Got used to the drone. Drag and drop from the view palette through the sheet. We've added a isometric veiw to this drawing, which by default uses the drawing sheet scale. We can modify the scale to one from the status bar on the bottom right screen. Because there's already been an exploded view, created the checkbox show and exploded or model break state as available and our view property manager. We can check this to change the view. Next we can add a bill of materials from the annotations tab under the tables dropdown for us to select the Drawing view to use, which will be the exploded view. Before using the green tick on the Property Manager to accept the BOM options and click and on the sheet to place. BOM can then be modified for example. Column title. Part number may be clearer if entitled. Name so we can double click and change. We may also want to show quantity of the parts before the description, and this can be done by dragging the columns across. The descriptions themselves. Currently only have a default value to change us to something more meaningful. Right click on a part and the BOM and choose to open. Once the part is open, we can select the File Properties icon from the toolbar, then the custom tab to change the value for the description property. When we okay the change and use the windows dropdown, navigate back to the drawing. We can see that the value has updated. The BOM columns can then be resized if necessary. The final step is to add balloons to indicate which item number, and the BOM is related to each component and the assembly. This could be done by selecting the balloon tool and manually add in each component, but auto balloon can also be used to quickly add a balloon for each component at the same time. When auto balloon is selected, a preview of the blends to be added can be seen. There are various options and the property manager, one of which is to change the layout of the balloons. Another useful option is the ability to order the balloons sequentially. This will renumber the balloons and reorder the BOM, meaning the numbers are ordered in a clockwise direction. We can then accept the command. Magnetic lines are also created, which enable us to drag and move multiple balloons at once. This enables us to quickly finalize the layout of our drone. Thank you for watching this quick introduction. Exploded views and BOMs using the SOLIDWORKS online trial.