In this video, we're going to be taking a look at the process behind creating five axis tool paths in SWOOD CAM intended for a five axis biesse pod and rail CNC machine. The geometry will be using today is this new post that you can see on screen. We're going to do this in two programs, one for the top face and a second program to address the bottom face and the two sides. As you can see, the first programs already been designated. But if I switch to the second program, you'll see, although we've set the orientation, the pod and rail positions and inserted the tools as of yet, we've not generated any tool paths within this program. The first geometry that I'm going to address, the three groves that we can see on the three sides, I'm going to do this with a ten mil bull tool I have three sketches I've pre drawn designating the position and orientation of these groups. I'm going to select the first sketch called Groups One and Choose Milling, Select my tool and Choose Move Tool Center. MOVE Tool Center operation essentially allows me to follow the sketch line with the center of my tool and click add want to do this in two passes of 1.5. So I'm going to say that I've got a depth of material of around three mil, and I want to do a number of passes here at 1.5 mil depth, click the green tick to accept, and I can then simulate assuming I'm happy with that. I can rename this to grooves Now to repeat the process on the to opposite sides, I will need to designate a new coordinate system to do this. I can use the preexisting face operations on the left hand side to start with. I will select face one and we can see the orientation of current system then changes. I can select the groove two operation and choose milling rather than going through the same process again. I can actually select an operation that pre exists within my program to reuse and insert, as you can see here, using the exact same operations step downs and parameters. I'll repeat that process again by choosing face three for the opposite sides. The third groove sketch and insert the grooves operation that exists within the job, as you can see. Then I can then simulate each of these operations as required to ensure that I'm happy with the final result. Now we've addressed the three grooves on the three sides. The next operation we want to look at is this curve face on the top end of the newel post. To do this a pre created a surface on the exact position as such. Generally within this would come we find a good idea to go through and generate surfaces to allow us to bound and control a five axis tool paths with some more control. In this case, I'll select the surface. I'll choose 3D milling from a toolbar on the top and again I'll select my time ball operation using finishing. I have a number of options within here, but the first thing I'm going to do is activate the five axis operation and set amount angle max of around 120 degrees. can choose the path direction and for this operation I'm going to choose the radial direction. I can change either the scallop with all the scallop depth, and for now I'll set the scallop width to about two mil. can change the direction of the face we're working from with the surface. And assuming I'm happy with the end result, I can click the green tick to accept. We can simulated this stage and ensure we're happy with the final result. The next tool we have on our list here is a 60 degree engraving cutter. Although you can't see at the moment. I have a number of logos pre added into this model. I have one for solid solutions, one for biesse and one for trimech. It within this would come. All we need is sketch text to allow us to introduce an engraving operation. I will select the Solid Solutions logo, choose milling, choose my engraving tool, and simply select the engraving operation. And add whilst I have a number of options to control this, the time being I'm going to leave this as default and click the green to accept. And again I can simulate to ensure I'm happy. I can repeat this process for the two of the logos And to finish, I'm going to add a shortcut to the far end to ensure that we square this up using the saw blade and a cut groove operation with a maximum step of around 50 mil to do two passes of 35 mil and again simulate to ensure I'm happy. The final stage is I can go in and drill these holes on the top and using the eight mil drill with a simple drill operation. Again simulating to ensure I'm happy with the final result. At this stage I can run the ENCODE option which will generate me a CNC program directly able to be loaded into the Biesse software, BSolid. This program .CIX can now be sent directly to the CNC Thank you for watching.